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How do I make sketches vanish from configurations?
Posted: Fri Jul 01, 2022 1:35 pm
by KSHansen
I'm working with someone else's model. I created twenty configurations before I realized there were two sketches that were not hidden, and they are visible in all my assembly configs. I have to find them in the feature tree and hide them, separately for each configuration. Is there a way to hide them in all configurations at once?
I see that there is a button to turn off display of all sketches, but can they actually be hidden in the model, while leaving others showing?
Re: How do I make sketches vanish from configurations?
Posted: Fri Jul 01, 2022 4:27 pm
by jcapriotti
I'm assuming that your "Display States" are linked to your configurations? If so, there is a Display State created and linked to each of your 20 configurations and that's where the visibility of feature tree references are stored. Unless you need to have different colors/appearances for each configuration, I recommend unlinking it so there is only one Display State.
If you need to keep them linked, I posted this old macro ( I didn't write it) here in the macro forum.
https://www.cadforum.net/viewtopic.php?t=2034
Re: How do I make sketches vanish from configurations?
Posted: Fri Jul 01, 2022 5:34 pm
by KSHansen
The model does have the different configurations in different colors. So assuming I want to keep it that way, how do I select a display state, to have it show up on the properties tab?
Re: How do I make sketches vanish from configurations?
Posted: Fri Jul 01, 2022 6:21 pm
by jcapriotti
If you have them linked...then no need. You can run the macro on the part and check the box "All configurations".
Re: How do I make sketches vanish from configurations?
Posted: Tue Jul 05, 2022 4:11 pm
by DanPihlaja
Here's what I do, in this order.....and honestly it doesn't take that much time.
1) CTRL + T (switches the history tree into flat tree view & exposes all the sketches that aren't part of a hole wizard)
2) Select top level and hit the * key. (this expands the hole wizard holes (and other such things))
then
3) Hit the little carat to expand the display pane (or hit F8)
- image.png (21.42 KiB) Viewed 585 times
4) Then walk down the "Hide" column and click hide for all the sketches that are shown
5) I do this for each configuration (I generally only have 10 or less....so if you have more....it might still be super tedious)
6) Once I am done, I hit SHIFT + C to collapse the tree again.
7) Hit CTRL + T again to take the tree out of flat tree view again.
8) Go have coffee.